{"id":986,"date":"2016-04-26T13:58:05","date_gmt":"2016-04-26T03:58:05","guid":{"rendered":"https:\/\/www.finiteelementanalysis.com.au\/?p=986"},"modified":"2016-04-26T13:58:05","modified_gmt":"2016-04-26T03:58:05","slug":"meshing-fabricated-structures-in-ansys-mechanical-using-mesh-edit","status":"publish","type":"post","link":"https:\/\/www.leapaust.com.au\/blog\/fea\/meshing-fabricated-structures-in-ansys-mechanical-using-mesh-edit\/","title":{"rendered":"Meshing Fabricated Structures in ANSYS Mechanical using Mesh Edit"},"content":{"rendered":"<div id=\"bsf_rt_marker\"><\/div><p><span style=\"font-size: 12pt;\">The introduction of parallel part-by-part meshing to ANSYS Mechanical 15 back in 2013 was revolutionary. Structures which took hours to mesh now wrapped up in minutes, unfortunately removing one of our favourite excuses for taking a tactical nap. One of the limitations to this new feature was the fact that Multibody parts were still meshed in serial. Given that customers in the maritime, aviation and defence industries all utilised Multibody parts to connect shell assemblies, this was a pretty big drawback.<\/span><\/p>\n<p><span style=\"font-size: 12pt;\">Introduced in R16 and refined in R17, ANSYS Inc have introduced a suite of tools focussed on \u201cmesh editing\u201d which work to enhance the workflow associated with meshing and connecting fabricated structures. Over the course of these two releases, a number of new features have been implemented:<\/span><\/p>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>Improved shell meshing for better structured meshes<\/strong><\/span><\/li>\n<\/ul>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2.png\"><img fetchpriority=\"high\" decoding=\"async\" class=\"alignnone wp-image-988 size-large\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2-1024x313.png\" alt=\"Improved shell meshing for better structured meshes \" width=\"838\" height=\"256\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2-1024x313.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2-300x92.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2-768x235.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_2-2.png 1118w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/a><\/p>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>Mesh edit tools for creating mesh connections post mesh generation<\/strong><\/span><\/li>\n<\/ul>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>Imprint tool in SpaceClaim to assist with the mesh connections approach to fabricated structures<\/strong><\/span><\/li>\n<\/ul>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_3-2.png\"><img decoding=\"async\" class=\"alignnone wp-image-989 size-full\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_3-2.png\" alt=\"Imprint tool in Spaceclaim to assist with the mesh connections approach to fabricated structures\" width=\"416\" height=\"117\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_3-2.png 416w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_3-2-300x84.png 300w\" sizes=\"(max-width: 416px) 100vw, 416px\" \/><\/a><\/p>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>The ability to display element quality on geometry as a contour plot<\/strong><\/span><\/li>\n<\/ul>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_4-2.png\"><img decoding=\"async\" class=\"alignnone wp-image-990 size-full\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_4-2.png\" alt=\"display element quality on geometry as a contour plot \" width=\"738\" height=\"545\" \/><\/a><\/p>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>Weld Tool added to SCDM and DM to create weld bodies connecting adjacent surfaces<\/strong><\/span><\/li>\n<\/ul>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-large wp-image-991\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2-1024x354.png\" alt=\"Weld Tool added to SCDM and DM to create weld bodies connecting adjacent surfaces\" width=\"838\" height=\"290\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2-1024x354.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2-300x104.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2-768x266.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_5-2.png 1278w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/a><\/p>\n<ul>\n<li><span style=\"font-size: 12pt;\"><strong>Detach operation added to SCDM and DM which can be used to split large surface bodies into multiple surface bodies for an improved local control of the mesh<\/strong><\/span><\/li>\n<\/ul>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-large wp-image-992\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1-1024x219.png\" alt=\"Detach operation added to split large surface bodies into multiple surface bodies\" width=\"838\" height=\"179\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1-1024x219.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1-300x64.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1-768x165.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_6-1.png 1241w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">The addition of these features produces an entirely new workflow for fabricated structures, allowing node-node connectivity in fabricated shell structures while making use of parallel meshing. The overall procedure involved in this new workflow is:<\/span><\/p>\n<ol>\n<li><span style=\"font-size: 12pt;\">Imprint mid-surface faces using Spaceclaim Direct Modeler.<\/span><\/li>\n<li><span style=\"font-size: 12pt;\">Import geometry into Mechanical, delete any contact regions generated in locations intended for mesh connections.<\/span><\/li>\n<li><span style=\"font-size: 12pt;\">Apply edge sizing to all imprinted edges (<em>this step isn\u2019t mandatory, however it will create cleaner connections in Mechanical<\/em>) and then generate the mesh.<\/span><\/li>\n<li><span style=\"font-size: 12pt;\">Merge adjacent nodes together using the Node Merge feature.<\/span><\/li>\n<\/ol>\n<p><span style=\"font-size: 12pt;\">The following steps aim to demonstrate the implementation of the key points outlined above. We will be explaining the procedure using the bracket shown below:<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_7-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone wp-image-993 size-medium\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_7-1-300x296.png\" alt=\"Bracket model for analysis in ANSYS\" width=\"300\" height=\"296\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_7-1-300x296.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_7-1.png 589w\" sizes=\"(max-width: 300px) 100vw, 300px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">Looking over the bracket, we can see that although the parts appear to be connected together, upon hiding the central stiffener, there are no imprinted edges where the intersection occurs with the parent material:<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_8-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone wp-image-994 size-medium\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_8-1-300x199.png\" alt=\"Bracket model with no imprinted edges\" width=\"300\" height=\"199\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_8-1-300x199.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_8-1-768x509.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_8-1.png 870w\" sizes=\"(max-width: 300px) 100vw, 300px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\"><strong>The Method<\/strong><\/span><\/p>\n<p><span style=\"font-size: 12pt;\"><strong><em>Imprinting Parts using SCDM<\/em><\/strong><\/span><\/p>\n<p><span style=\"font-size: 12pt;\">The first order of business is to imprint any edges which are in contact with adjacent faces, forcing the Mechanical mesher to place nodes on both sides of interface regions.<\/span><\/p>\n<p><span style=\"font-size: 12pt;\">SpaceClaim makes this process simple;<\/span><\/p>\n<p><span style=\"font-size: 12pt;\">1. Select the\u00a0<em>Prepare\u00a0<\/em>Tab.<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_9-2.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-full wp-image-1016\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_9-2.png\" alt=\"SpaceClaim's Imprint feature on the prepare tab \" width=\"950\" height=\"114\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_9-2.png 950w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_9-2-300x36.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_9-2-768x92.png 768w\" sizes=\"(max-width: 950px) 100vw, 950px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">2.\u00a0Choose the <em>Imprint<\/em> button \u2013 this will detect any face\/edge pairs which are within a user nominated tolerance and highlight them in red. Apply these changes.<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_10-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-full wp-image-996\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_10-1.png\" alt=\"Detection of face\/edge pairs in ANSYS SpaceClaim Design Modeler\" width=\"576\" height=\"399\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_10-1.png 576w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_10-1-300x208.png 300w\" sizes=\"(max-width: 576px) 100vw, 576px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">3.\u00a0When hiding adjacent bodies you will now see the imprinted edges on parent faces (see bottom image). The geometry is now ready to be sent through to Mechanical for meshing.<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_11-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-full wp-image-997\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_11-1.png\" alt=\"Imprinted edges on parent faces\" width=\"395\" height=\"401\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\"><em><strong>Importing Geometry into Mechanical<\/strong><\/em><\/span><\/p>\n<p><span style=\"font-size: 12pt;\">When the geometry is imported into Mechanical we can immediately see that the bodies comprising this assembly aren\u2019t unified within a single Multibody part.<\/span><\/p>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_12-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-full wp-image-998\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_12-1.png\" alt=\"Bracket model imported into ANSYS mechanical\" width=\"414\" height=\"327\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_12-1.png 414w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_12-1-300x237.png 300w\" sizes=\"(max-width: 414px) 100vw, 414px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">In this case no contact regions have been defined as the Edge-Face contact has been disabled as a default option. If Edge-Face contact regions are generated, suppress these contacts as our Mesh Connections will make them redundant.<\/span><\/p>\n<p><span style=\"font-size: 12pt;\"><em><strong>Meshing<\/strong><\/em><\/span><\/p>\n<p><span style=\"font-size: 12pt;\">First of all we\u2019ll need a reasonable quality mesh for the Mesh Connection feature. Although this step is optional we highly recommend it.<\/span><\/p>\n<ol>\n<li><span style=\"font-size: 12pt;\">Select all edge pairs which we intend to merge using Mesh Connections.<\/span><\/li>\n<li><span style=\"font-size: 12pt;\">Apply a sensible Edge Sizing to these edge pairs, ensuring the Behaviour is set to \u201cHard\u201d \u2013 this will guarantee nodes will be in similar positions along the length of each edge.<\/span><\/li>\n<li><span style=\"font-size: 12pt;\">Generate the mesh<\/span><\/li>\n<\/ol>\n<p><a href=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_13-1.png\"><img loading=\"lazy\" decoding=\"async\" class=\"alignnone size-full wp-image-999\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_13-1.png\" alt=\"Mesh generation for bracket model in ANSYS\" width=\"706\" height=\"659\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_13-1.png 706w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_13-1-300x280.png 300w\" sizes=\"(max-width: 706px) 100vw, 706px\" \/><\/a><\/p>\n<p><span style=\"font-size: 12pt;\">Observing the completed mesh, we can see that the Edge Sizing has forced nodes on either side of each edge pair to lie at similar positions along the length of the edge. At this stage these nodes, although coincident, are not connected together.<\/span><\/p>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"size-large wp-image-1000 alignleft\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_14-1-1024x319.png\" alt=\"Pic_14\" width=\"838\" height=\"261\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_14-1-1024x319.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_14-1-300x93.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_14-1-768x239.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_14-1.png 1128w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/p>\n<p>The Mesh Connections tools will merge nodes within a given user defined tolerance to complete the workflow.<\/p>\n<p><span style=\"font-size: 12pt;\"><em><strong>Mesh Connections<\/strong><\/em><\/span><\/p>\n<ol>\n<li><span style=\"font-size: 12pt;\">Right click on \u00a0Mesh branch of the tree &gt; Insert &gt; Node Merge Group<\/span><\/li>\n<\/ol>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"aligncenter size-full wp-image-1001\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_15-1.png\" alt=\"Node Merge group option in ANSYS 17.0\" width=\"625\" height=\"387\" \/><\/p>\n<p><span style=\"font-size: 12pt;\">2. \u00a0 Choose a suitable tolerance value inside of which any nodes will be merged together. In our case we have chosen 0.1 mm as our edge sizing has ensured nodes are coincident. If the edge sizing step was skipped, a looser tolerance will be needed which could result in a poorer quality mesh. Care must be taken not to loosen the tolerance too far, as it may result in collapsed elements leading to solver issues.<\/span><\/p>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"aligncenter size-full wp-image-1030\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_16-2.png\" alt=\"Mesh Generation within ANSYS 17.0\" width=\"323\" height=\"137\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_16-2.png 323w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_16-2-300x127.png 300w\" sizes=\"(max-width: 323px) 100vw, 323px\" \/><\/p>\n<p><span style=\"font-size: 12pt;\">3. Right click on the Node Merge Group and click Generate<\/span><\/p>\n<p><span style=\"font-size: 12pt;\">Once the Node Merge has completed, the Message window below the graphics window will report how many nodes were merged as a result of the operation:<\/span><\/p>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"aligncenter size-full wp-image-1033\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_19-1.png\" alt=\"Automatic node merge operation results\" width=\"668\" height=\"104\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_19-1.png 668w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_19-1-300x47.png 300w\" sizes=\"(max-width: 668px) 100vw, 668px\" \/><\/p>\n<p><span style=\"font-size: 12pt;\">We can see the effect of this operation on the mesh by inspecting the edge connectivity plot before and after the node merge was completed in the following image. A red edge corresponds to an edge connected to only one face, whereas the purple edge in the second image indicates a single edge connected to multiple faces.<\/span><\/p>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"aligncenter size-large wp-image-1003\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_17-1-1024x329.png\" alt=\"Results of automatic meshing in ANSYS 17.0\" width=\"838\" height=\"269\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_17-1-1024x329.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_17-1-300x96.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_17-1-768x247.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_17-1.png 1099w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/p>\n<p><span style=\"font-size: 12pt;\">This concludes the procedure explaining how to connect fabricated structures using the Node Merge feature within ANSYS Mechanical, allowing users to access the performance of parallel meshing while still retaining node-node connectivity.<\/span><\/p>\n<p><img loading=\"lazy\" decoding=\"async\" class=\"aligncenter size-large wp-image-1004\" src=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_18-1-1024x392.png\" alt=\"Pic_18\" width=\"838\" height=\"321\" srcset=\"https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_18-1-1024x392.png 1024w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_18-1-300x115.png 300w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_18-1-768x294.png 768w, https:\/\/www.leapaust.com.au\/blog\/wp-content\/uploads\/2016\/04\/Pic_18-1.png 1456w\" sizes=\"(max-width: 838px) 100vw, 838px\" \/><\/p>\n<p>&nbsp;<\/p>\n<p>&nbsp;<\/p>\n","protected":false},"excerpt":{"rendered":"<p>The introduction of parallel part-by-part meshing to ANSYS Mechanical 15 back in 2013 was revolutionary. Structures which took hours to mesh now wrapped up in minutes, unfortunately removing one of our favourite excuses for taking a tactical nap. One of the limitations to this new feature was the fact that Multibody parts were still meshed&hellip;&nbsp;<a href=\"https:\/\/www.leapaust.com.au\/blog\/fea\/meshing-fabricated-structures-in-ansys-mechanical-using-mesh-edit\/\" rel=\"bookmark\">Read More &raquo;<span class=\"screen-reader-text\">Meshing Fabricated Structures in ANSYS Mechanical using Mesh Edit<\/span><\/a><\/p>\n","protected":false},"author":0,"featured_media":1005,"comment_status":"open","ping_status":"open","sticky":false,"template":"","format":"standard","meta":{"neve_meta_sidebar":"","neve_meta_container":"","neve_meta_enable_content_width":"","neve_meta_content_width":0,"neve_meta_title_alignment":"","neve_meta_author_avatar":"","neve_post_elements_order":"","neve_meta_disable_header":"","neve_meta_disable_footer":"","neve_meta_disable_title":"","neve_meta_reading_time":"","footnotes":""},"categories":[144],"tags":[171,172,180,185,42,220,249,292],"class_list":["post-986","post","type-post","status-publish","format-standard","has-post-thumbnail","hentry","category-fea","tag-ansys","tag-ansys-17-0","tag-ansys-mechanical","tag-ansys-workbench","tag-fea","tag-finite-element-analysis","tag-meshing","tag-spaceclaim"],"_links":{"self":[{"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/posts\/986","targetHints":{"allow":["GET"]}}],"collection":[{"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/posts"}],"about":[{"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/types\/post"}],"replies":[{"embeddable":true,"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/comments?post=986"}],"version-history":[{"count":0,"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/posts\/986\/revisions"}],"wp:featuredmedia":[{"embeddable":true,"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/media\/1005"}],"wp:attachment":[{"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/media?parent=986"}],"wp:term":[{"taxonomy":"category","embeddable":true,"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/categories?post=986"},{"taxonomy":"post_tag","embeddable":true,"href":"https:\/\/www.leapaust.com.au\/blog\/wp-json\/wp\/v2\/tags?post=986"}],"curies":[{"name":"wp","href":"https:\/\/api.w.org\/{rel}","templated":true}]}}